Tap Drill & Clearance Hole Chart

Pick a thread to get the drill to tap it, the hole a bolt of that size passes through, and the limits the tapped hole has to meet. Enter the drill you have to check it before you start.

Thread
Thread size
in
Enter the drill diameter in inches; we work out the thread percentage.
Tap drill and clearance holes
#70.2010 in · 5.11 mm
Tap drill for 1/4-20 UNC, about 75% thread
Major diameter0.2500 in · 6.35 mm
Threads per inch20
Clearance hole, close fitF · 0.2570 in · 6.53 mm
Clearance hole, free fitH · 0.2660 in · 6.76 mm

Inch tap drills are the nearest standard drill to a 75% thread (UNC/UNF, ASME B1.1). The thread percentage is worked out for the drill shown.

Metric clearance holes follow ISO 273: close, normal and loose correspond to the fine, medium and coarse series (H12, H13, H14). Inch clearance drills are the common close and free shop sizes.

UNC and UNF threads: tap drill and clearance drills
Thread sizeTap drillinThreadClearance closeClearance free
#0-80 UNF3/640.046981%#52#50
#1-64 UNC#530.059567%#48#46
#1-72 UNF#530.059575%#48#46
#2-56 UNC#500.070069%#43#41
#2-64 UNF#500.070079%#43#41
#3-48 UNC#470.078576%#37#35
#3-56 UNF#450.082073%#37#35
#4-40 UNC#430.089071%#32#30
#4-48 UNF#420.093568%#32#30
#5-40 UNC#380.101572%#30#29
#5-44 UNF#370.104071%#30#29
#6-32 UNC#360.106578%#27#25
#6-40 UNF#330.113077%#27#25
#8-32 UNC#290.136069%#18#16
#8-36 UNF#290.136078%#18#16
#10-24 UNC#250.149575%#9#7
#10-32 UNF#210.159076%#9#7
#12-24 UNC#160.177072%#2#1
#12-28 UNF#140.182073%#2#1
1/4-20 UNC#70.201075%FH
1/4-28 UNF#30.213080%FH
5/16-18 UNCF0.257077%PQ
5/16-24 UNFI0.272075%PQ
3/8-16 UNC5/160.312577%WX
3/8-24 UNFQ0.332079%WX
7/16-14 UNCU0.368075%29/6415/32
7/16-20 UNF25/640.390672%29/6415/32
1/2-13 UNC27/640.421978%33/6417/32
1/2-20 UNF29/640.453172%33/6417/32
9/16-12 UNC31/640.484472%37/6419/32
9/16-18 UNF33/640.515665%37/6419/32
5/8-11 UNC17/320.531379%41/6421/32
5/8-18 UNF37/640.578165%41/6421/32
3/4-10 UNC21/320.656372%49/6425/32
3/4-16 UNF11/160.687577%49/6425/32
7/8-9 UNC49/640.765676%57/6429/32
7/8-14 UNF13/160.812567%57/6429/32
1-8 UNC7/80.875077%1-1/641-1/32
1-12 UNF59/640.921972%1-1/641-1/32

Mark the holes on the part photo

Put the thread callouts, hole sizes and counts on a photo of the real bracket or flange, so nobody taps an M8 where a 9 mm clearance hole was meant.

Metric tap drill and clearance hole chart

The most-asked coarse threads. The tap drill makes the hole you cut the thread in; the clearance hole is the one the bolt passes through.

ThreadTap drill (mm)6H minor diameter (mm)Clearance closeClearance normalClearance loose
M3 × 0.52.52.459–2.5993.23.43.6
M4 × 0.73.33.242–3.4224.34.54.8
M5 × 0.84.24.134–4.3345.35.55.8
M6 × 154.917–5.1536.46.67
M8 × 1.256.86.647–6.9128.4910
M10 × 1.58.58.376–8.67610.51112
M12 × 1.7510.210.106–10.4411313.514.5
M16 × 21413.835–14.2101717.518.5
M20 × 2.517.517.294–17.744212224
M24 × 32120.752–21.252252628

Clearance holes are ISO 273 fine, medium and coarse series (H12, H13, H14). The calculator above covers M1.6 to M56 coarse, common fine threads and clearance holes up to M64.

Tap drill or clearance hole: which one do you need?

  • Tap drill: the hole is threaded, so it is smaller than the bolt. For M8 × 1.25 that is 6.8 mm.
  • Clearance hole: the bolt passes through and a nut or a tapped part on the other side holds it, so the hole is larger than the bolt. For M8 that is 8.4, 9 or 10 mm depending on the fit.
  • Close clearance locates parts accurately but needs good hole positions. Normal is the default for general assembly. Loose allows for misalignment, slotted parts and field assembly. Our clearance hole article explains when each one fits.
  • A drawing that says “Ø8” for an M8 bolt specifies a hole the bolt will not pass through. Write the clearance size, or “M8 tapped” if the hole is threaded.

UNC and UNF tap drill chart

Tap drills for about 75% thread, the usual shop choice, with the close and free clearance drills for the same screw size.

ThreadTap drillDecimal (in)ThreadClearance closeClearance free
#4-40 UNC#430.089071%#32#30
#6-32 UNC#360.106578%#27#25
#8-32 UNC#290.136069%#18#16
#10-24 UNC#250.149575%#9#7
#10-32 UNF#210.159076%#9#7
1/4-20 UNC#70.201075%FH
1/4-28 UNF#30.213080%FH
5/16-18 UNCF0.257077%PQ
3/8-16 UNC5/160.312577%WX
3/8-24 UNFQ0.332079%WX
1/2-13 UNC27/640.421978%33/6417/32
5/8-11 UNC17/320.531379%41/6421/32
3/4-10 UNC21/320.656372%49/6425/32

Number and letter drill diameters follow ASME B94.11M. Charts differ by one drill size on a few threads (#10-24 is #25 or #26); the thread percentage tells you how full the thread will be.

How the sizes are worked out

Metric tap drills follow ISO 2306, which recommends a drill close to nominal diameter minus pitch: 8 − 1.25 = 6.75, so M8 takes a 6.8 mm drill. The tapped hole then has to fall within the 6H minor diameter: at least D − 1.0825 × pitch (6.647 mm for M8, ISO 724) and at most that plus the grade-6 tolerance from ISO 965-1 (6.912 mm).

Inch tap drills use the shop formula for a target thread percentage: drill = major diameter − 0.01299 × percentage ÷ threads per inch. For 1/4-20 at 75% that is 0.2013 in, and the nearest standard drill is #7 (0.201 in).

Clearance holes come from ISO 273 for metric bolts and from the common close and free shop sizes for inch screws. We checked the tables against AmesWeb (after Machinery's Handbook), TR Fastenings, Tameson and the University of Florida design lab chart, and only kept sizes where at least two of them agree.

Writing holes on a drawing or quote

  • Give the count, the thread and the depth: 4 × M8 – 6H, 15 deep, or 4 × M8 through.
  • For clearance holes, give the diameter and the fit if it matters: 4 × Ø9 (ISO 273 medium).
  • Inch threads carry the series and class: 1/4-20 UNC-2B for an internal thread.
  • If the buyer will fit their own bolts, say which bolt the hole is for, not just the diameter.

Frequently asked questions

What size drill do I need for an M8 tap?

6.8 mm for the standard M8 × 1.25 coarse thread. For the fine M8 × 1 thread use 7.0 mm. The tapped hole must end up between 6.647 and 6.912 mm (6H minor diameter) for M8 × 1.25.

What size clearance hole for an M6 bolt?

6.4 mm for a close fit, 6.6 mm for a normal fit and 7.0 mm for a loose fit (ISO 273). Use 6.6 mm unless the parts must locate on the bolt or need room to adjust.

What drill do I use for a 1/4-20 tap?

A #7 drill (0.201 in), which gives about 75% thread. A 13/64 in drill (0.2031 in) is the nearest fractional size and gives a slightly shallower thread.

Can I use a slightly larger tap drill in hard material?

Often, yes. A larger drill makes tapping easier and still gives a sound thread as long as the hole stays within the 6H minor diameter. Enter your drill in the check box to see whether it does.

What does 6H mean on a metric thread?

It is the tolerance class of an internal thread under ISO 965-1: 6 is the tolerance grade and H means no allowance. It is the normal class for nuts and tapped holes, and it pairs with 6g on bolts.

Other free tools

Tap Drill Chart & Clearance Hole Chart: Metric and UNC/UNF | SizeMarker